TAD 330- Making Isometric & Exploded Assembly View Drawings
Intro: TAD 330- Making Isometric & Exploded Assembly View Drawings
The following will show you how to create the first two pages of the engineering design packet for TAD 330, which are the isometric & exploded views of a completed assembly.
STEP 1: In Inventor, Create a New Drawing (.idw).
- Open Inventor.
- Select File->New->Drawing
- Click ANSI (mm).idw
STEP 2: Format the Drawing Size
- Under the "Drawing Resources" tab,
- Select "Sheet Formats"
- Select "B Size, 2 view"
- Select "Sheet Formats"
STEP 3: Import Your Assembly File Into the Drawing
- After selecting B size, a prompt will appear to select the document you wish to include in the drawing.
- Select the document.
- Click "Open", then click "OK".
STEP 4: Open the Drawing and Delete View 1
- Delete the view that Inventor automatically applies, since an isometric view of the assembly is needed.
STEP 5: Under "place Views", Create a New Base View
STEP 6: Format the New Base View
- The view will need to be adjusted so that it is isometric.
- Click the "Home" icon on the navigation cube to orient it correctly.
- The scale used in this example is 1/2
- The correct style for all isometric projections is shaded with no hidden lines visible.
- Click "OK" once all of the above steps have been completed.
STEP 7: Center the Isometric Base View
- Center the isometric projection of the assembly to make it look presentable.
- Remember, this is the very first page of the design packet!
STEP 8: Create a Text Box & Fill Out Title Block Info
- Under the "Annotate" tab, click on "Text"
- This will allow you to create a text box anywhere on the drawing.
- In the box above the "TITLE" block, make a text box and type "BEREA COLLEGE" in 9.53mm font.
- In the larger title box below, make a text box and put the name of the assembly in 7mm font.
- In this example, it is the Leveling Assembly from Chapter 12.
STEP 9: Create a New Sheet for Page 2-- the Exploded Assembly View
- Under "Place Views", click "New Sheet".
STEP 10: In Order to Create an Exploded View of the Assembly, Create a Presentation
- "File"-->"New"-->Presentation--> Standard (mm).ipn
- Click "Create".
STEP 11: In the Presentation, Select the Assembly File.
- Once the assembly file has been selected, click "Open".
STEP 12: Explode the Assembly
- To explode the assembly, click "Tweak Components".
STEP 13: Select and Explode Multiple Parts
- While holding down the "Ctrl" key, select the parts which you would like to move together.
STEP 14: Tweak the Lifting Block Up 180 Mm
- Ensure that both "Tweak Components" and the Lifting Block part are selected.
- Click on the direction arrow pointing upwards (Y-axis).
- In the dialog box, type in "180".
- The part will then move upwards by 180mm.
- Click the green check to confirm this movement.
STEP 15: Tweak the Sliding Block and Adjusting Screw Up 120 Mm
- Ensure "Tweak Components" is selected.
- Use Ctrl + click to select both the Sliding Block and Adjusting Screw.
- Click on the direction arrow pointing upwards (Y-axis).
- In the dialog box, type in "120".
- The parts will then move upwards by 120mm.
- Click the green check to confirm this movement.
STEP 16: Tweak the Adjusting Screw 100 Mm to the Right
- Ensure "Tweak Components" is selected.
- Select the Adjusting Screw.
- Click on the direction arrow pointing to the right (Z-axis).
- In the dialog box, type in "100".
- The part will then move 100mm to the right.
- Click the green check to confirm this movement.
STEP 17: Be Sure That the View of Individual Parts Is Unobstructed.
STEP 18: Take a Snapshot View of the Fully Tweaked Assembly.
- Under "Presentation", click "New Snapshot View".
- This will take a snapshot of the tweaked assembly, so it can be used in a drawing.
STEP 19: Save the Presentation File.
STEP 20: Import the Snapshot View to the Drawing.
- On Sheet 2 under "Place Views", click "Base"
- The exploded assembly should automatically pop up.
- If it does not, search for the right file before continuing.
STEP 21: Format the Exploded View.
- Be sure to format and orient this exploded view in the same way as the non-exploded isometric view on page 1.
- No hidden lines, shaded, and same scale (in this example, 1/2).
- Offset this view to the left side a bit as room will be needed to fit the parts list and balloons.
- Click "OK".
STEP 22: Create a Parts List.
- Under "Annotate", select "PartsList".
- Select the exploded view as the document you wish to have a Parts List for.
- Click "OK".
- An outline of the Parts List box will appear; drag this to the top right corner of the drawing.
STEP 23: Edit the Parts List to Include "Material" Column Instead of "Description"
- To execute this, double-click on the Parts List.
- A dialog box will pop up.
- In this box, select "ColumnChooser" (the leftmost button).
- In the "Selected Properties" column, click on "Description", then select "Remove".
- Under "Available Properties", click on "Material", then select "Add" to add it to the "Selected Properties" list.
- Click "OK".
STEP 24: Neaten the Parts List
- Get rid of unnecessary spaces in the parts list by dragging the columns left or right to minimize them.
STEP 25: Under "Annotate", Select "Auto Balloon".
- Balloons will allow the parts in the exploded assembly to be easily identified and compared against the parts list.
STEP 26: Click All Parts in the Assembly to Automatically Bring Up the Balloons
- To make sure all of the parts in the assembly have a balloon, ensure that when a part is selected, it turns blue.
- All the blue-outlined parts will have a balloon designated to them.
STEP 27: Right Click, Then Click Continue
STEP 28: Drag the Balloons Away From the Exploded View, Then Click to Place Them.
- After placing the balloons, click "OK".
STEP 29: Neaten the Balloons
- For maximum neatness, ensure that the balloons are somewhat aligned to each other, or that their lines are parallel.
STEP 30: Place Title Block Information.
- Instead of creating new text boxes for sheet 2 and typing the same information, the text boxes created in sheet 1 can be copied and pasted into the title block in sheet 2.
- When pasting the copied boxes into sheet 2, the outline of two boxes will appear in green.
- Align them within the title blocks and then left-click to paste.
- Press the "Esc" key once complete.
STEP 31: Page 1 Isometric Assembly View and Page 2 Exploded Isometric Assembly View Complete
- The first two pages of the engineering design packet are now complete.
Comments
Elaina M 4 years ago